best technique to make holes with heads

[mandorlim]

Hello, I am learning to use pro/engineer wf4, and I asked users who use this cad which technique they recommend for the execution of multiple smooth holes or threads that are.
I try to make an example:
I have a sheet plate on which I have to go to perform a whole set of holes not necessarily pattern.
with other cads (solidworks and inventor), the function creates hole is based on a sketch, then you create the sketch, and you go to select the remarkable points where you want to create the hole. with the same function I can then create 1 or more holes regardless of the points I created in the sketch.

with proe, the hole function allows me to place only one at a time, giving it references from time to time, or is there something wrong?
and then you have to resort to the pattern function, to create a series...
but if the holes I have to create are not in series? How is it better to proceed?
repeat the hole from time to time giving it references? or create datum axes based on a sketch and take them as reference for holes?
Thank you.

 

[Parametric_Ozzy]

Riciao.. .
I have to admit that you're a little unlucky at version level.
in the wf4 there was not this possibility from the wf5 onwards they also implemented this.
you have 4 possibilities anyway:

1- if your holes are listed by common references (stessa x e y) use table series
2- ctrl+c + ctrl+v and recopy the holes without having to remake the same command each time, here you can also set different references and choose whether to make them dependent or dependent on the original.
3- Use the extrusion command and then file, but here you will not have the tip depth option and all other options.
4-pass to a more up-to-date version, in the wf5 you have the set for points.

I hope I've been clear enough
greetings

 

[DANI-3D]

Hi.
with pro-e you can do more or less like the other cads with the extrusion command, but I recommend you use the special hole command, especially for threaded holes. Moreover it is good standard, when possible, to use the serial command, for the unregular series you can use that table, so doing, for the following series you can use the reference ones, for example if in a set positions a screw on the first hole of the series, the screws will follow the series of holes.

 

[mandorlim]

thanks and all for the answers.
Unfortunately, I have to use wf4, as the client company uses that.
in fact the problem arises when the holes cannot be made in series.
for the table series, it is very intuitive and uncomfortable if you are planning a machine, it is okay if you have to copy a particular, but in the design I find more comfortable the sketch as you can create references in a very simple way ...
Thank you.
Mandorlim

 

[Parametric_Ozzy]

thanks and all for the answers.
Unfortunately, I have to use wf4, as the client company uses that.
in fact the problem arises when the holes cannot be made in series.
for the table series, it is very intuitive and uncomfortable if you are planning a machine, it is okay if you have to copy a particular, but in the design I find more comfortable the sketch as you can create references in a very simple way ...
Thank you.
Mandorlim

What is not intuitive in a table series?
once you make the odds you show them and you can change them to your liking as if you were working in sketches.
use the paste copy if you have to give new references, at least the definition of the holes is always the same, you only have to stick the handles in the two linear surfaces.

 

[mandorlim]

There's nothing wrong, just it's my personal preference.
as you wrote, in the table series you are bound to the two x and y references... I can not add it as in the sketch.
ok, for the paste copy, provided that the hole that I copy is not already inserted in a series, in that case it does not make me copy it ..., but it should be enough to suppress the series, make the copy paste and reactivate, (I think, I have to try)
I hope that what I write, is not understood as a criticism, on the contrary I am eager to learn .... and thank you very much for the answers you give me. I hope in the future that I can contribute to this forum.

 

[Parametric_Ozzy]

There's nothing wrong, just it's my personal preference.
as you wrote, in the table series you are bound to the two x and y references... I can not add it as in the sketch.
ok, for the paste copy, provided that the hole that I copy is not already inserted in a series, in that case it does not make me copy it ..., but it should be enough to suppress the series, make the copy paste and reactivate, (I think, I have to try)
I hope that what I write, is not understood as a criticism, on the contrary I am eager to learn .... and thank you very much for the answers you give me. I hope in the future that I can contribute to this forum.

do not worry is not understood as critical, but some adjectives that you give (just intuitive, uncomfortable, etc.) personally I do not like, because you have to take your hand first here.
That said they implemented the command in wf5 on purpose, just because it was a lack "banal" I would say, so I am the first to tell you that it wanted, but there is more and more of a solution to solve it, more or less convenient to always depend on the points of view.

greetings

 

[massimo78]

3 months late and maybe I didn't even understand the question well or maybe it's what parametric_ozzy said it was implemented by 5, but cmq...

I personally create in a sketch all points of reference of the equal holes, for example in a sketch all the holes m8, in another all the holes ø10 etc.
then use the hole command to realize the first hole and then create the series with "points"
the thing is convenient to me especially when you put on the table because it directly creates the hole table

only problem is that, and I don't know why, 8 times out of 10 in creating the series duplicates my first hole

 

[Parametric_Ozzy]

3 months late and maybe I didn't even understand the question well or maybe it's what parametric_ozzy said it was implemented by 5, but cmq...

I personally create in a sketch all points of reference of the equal holes, for example in a sketch all the holes m8, in another all the holes ø10 etc.
then use the hole command to realize the first hole and then create the series with "points"
the thing is convenient to me especially when you put on the table because it directly creates the hole table

only problem is that, and I don't know why, 8 times out of 10 in creating the series duplicates my first hole

I was exactly referring to the series for points that still did not exist in the wf4 and therefore it was necessary to resort to series of table or to copy and paste different.

the set for sketch points instead is the ideal solution provided you have the wf5 or higher. :wink:

 

[massimo78]

Okay, sorry, then.
at this point I take advantage and ask you:
You know why, in creating the series, sometimes you duplicate my starting hole?
Suppose I have 10 points
I create the first hole, I create the series and the series turns out to me of 11 holes because the original hole is 2 times

 

[Parametric_Ozzy]

Okay, sorry, then.
at this point I take advantage and ask you:
You know why, in creating the series, sometimes you duplicate my starting hole?
Suppose I have 10 points
I create the first hole, I create the series and the series turns out to me of 11 holes because the original hole is 2 times

but it's strange as behavior.. the only thing I feel to tell you is to ensure you take as the first reference for the positioning of the first hole, the first point created of the sketch series and then in the series for points always select the same.
greetings

 

[sh4d3]

hello to all, I reopen the discussion for a similar problem: I need to drill a curved surface with an elliptical hole. I then open the 'form' sketcher, inside the hole cards. I define a vertical axis and the ellipse; confirming the warning 'there is no normal entity to the axis of revolution': What do you expect to define proe (wf5)? What normal entity should I create?
I don't even understand why I need to define an axis, but it's probably because I recently entered the world of Cadadists. .

Thanks

 

[MORENO100]

Hello, I am learning to use pro/engineer wf4, and I asked users who use this cad which technique they recommend for the execution of multiple smooth holes or threads that are.
I try to make an example:
I have a sheet plate on which I have to go to perform a whole set of holes not necessarily pattern.
with other cads (solidworks and inventor), the function creates hole is based on a sketch, then you create the sketch, and you go to select the remarkable points where you want to create the hole. with the same function I can then create 1 or more holes regardless of the points I created in the sketch.

with proe, the hole function allows me to place only one at a time, giving it references from time to time, or is there something wrong?
and then you have to resort to the pattern function, to create a series...
but if the holes I have to create are not in series? How is it better to proceed?
repeat the hole from time to time giving it references? or create datum axes based on a sketch and take them as reference for holes?
Thank you.

Hello mandorlim,
Sorry I'm late, but I just read the discussion now.
I use wf5 and I hope wf4 is equal... .
to lay a set of threaded holes use in 90% this method:
- I create a reference sketch (insert > reference model > sketch...)
- using the "point geometry" command I define the positions of my holes
- I create my first threaded hole with reference to a point, generally the first created.
- copy and paste it on the other points using the special glue comado (make sure you have the check on the "dependent copy" and "advanced reference configuration")

I think this is the most "versatile" method.
Lets know if something isn't clear to you.
p.s. if the method you liked, I strongly invite you to create a macro to create the reference sketch, macros to create threads (e.g., one per thread m3, one per thread m4, etc...) and a macro for the special glue (previous that this will be the most ruddy because wrapped the settings jump. ...