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gestione layer

  • Thread starter Thread starter Lis
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Lis

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Good morning to all,
I am a neophyte of catia v5 r19 and I have difficulty understanding the management of layers. for years I have used pro-e, which has a tree in which all layers are visible and with contextual menus modified their characteristics.
something like that?
If not how do you do it?

thanks to everyone for the availability.

nb: thanks also for many solutions to other problems found around the forum. :smile:

greetings
Lisa
 
in caia there is the management of the layers....... I have to say that I've found it very hostical... in autocad things are much simpler and more immediate.

for the correct use of layers you also need to use display filters (menu' tools).

for any clarification on the use of layers is better if you indicate a practical example in which you would like to use them so is the good time that this topic is deepened
 
I hardly know catia v5 for nothing, but all customers who use it and value nx tell me "but why use the nx layers? I'm old... in catia are not used, replaced by geometry set".
 
for geometry set I think you mean geometric groups....... Catia use and geometric groups practically always but I can assure you that the layers can give you something extra
 
Yes, I mean those.
I believe that there is the fact that in every company there are special practices and it seems that the rest is not there.
ps. I'm allergic to layers, too. I practically never use them.
 
The_Matrix said:
I hardly know catia v5 for nothing, but all customers who use it and value nx tell me "but why use the nx layers? It's old stuff. in catia are not used, replaced by geometry set".
Click to expand...
... and in fact it is true ... there are geometric sets or partbody that surely for the caty user are very comfortable as they allow to give a name to things, so in the structure of the tree are more immediate identification and understanding.
the layers are there, but they are not at all practical to use: It is an evident involution compared to v4 and despite the speech of geometric groups, this does not justify this serious lack. even less expensive cads have windows where simply popping up a box you activate or not the desired layers, without having to invent filters or other strange menades. . .
(so to make an example rhino has a simple, practical and functional system).
then as in the world there are also other systems besides catia, which dialogue among themselves using non-native formats such as iges for example,
then the use of layers to divide the various parts becomes essential.
that finally tell of the import of iges files from other systems operating with layers: practically unmanageable, a unique geometric group is created with everything inside. with a nice loss of time, by hand, using the "find" for layers, color etc..., if everything works, maybe you can divide the entities and manage them by moving them into further geometric groups. . .

:frown:

greetings
tvi71
 
tvi71it said:
... and in fact it is true ... there are geometric sets or partbody that surely for the caty user are very comfortable as they allow to give a name to things, so in the structure of the tree are more immediate identification and understanding.
the layers are there, but they are not at all practical to use: It is an evident involution compared to v4 and despite the speech of geometric groups, this does not justify this serious lack. even less expensive cads have windows where simply popping up a box you activate or not the desired layers, without having to invent filters or other strange menades. . .
(so to make an example rhino has a simple, practical and functional system).
then as in the world there are also other systems besides catia, which dialogue among themselves using non-native formats such as iges for example,
then the use of layers to divide the various parts becomes essential.
that finally tell of the import of iges files from other systems operating with layers: practically unmanageable, a unique geometric group is created with everything inside. with a nice loss of time, by hand, using the "find" for layers, color etc..., if everything works, maybe you can divide the entities and manage them by moving them into further geometric groups. . .

:frown:

greetings
tvi71
Click to expand...
That's the kind of feedback I had.
I opened in section nx a survey to understand how many they use them and how many do not... If you want to participate. . .
 
Maybe we're all saying the same thing....... .
in everyday use, the exhilation of geometric groups is a real manna........ are easy and immediate use.......

in some particular situations (in which I found myself) instead the use of the layers is absolutely necessary....
I was accustomed to the ease of management of the same in autocad

I have actually noticed how much counteract can be their use.
 
thank you for being quick to answer! :

I clarify my intention better:
I have a set where components are happy with planes, surfaces, points, etc. for building parts. as they are all turned on the axieme is very "sporty", I had thought to create layers in which to close the various entities so that they can turn off and turn on at will.
Is that okay?
or did I do wrong?

Hi.
Lisa
 
for this simple case maybe it's better if you use geometric groups..... create one, rename it
then go to the entity you want to move (line sketch plane etc.). ) button inside and choose change geometric group
when you've done select the geometric group and hide it until you need it again
 
peloritano said:
for this simple case maybe it's better if you use geometric groups..... create one, rename it
then go to the entity you want to move (line sketch plane etc.). ) button inside and choose change geometric group
when you've done select the geometric group and hide it until you need it again
Click to expand...
excuse ignorance, but how do you create geometric groups in the axieme?
the assembly in question is composed of many parts, if the groups I have to create them in the individual parts I will put about 2000 years!!!!:eek:
 
bhe then explained better......
if you talk about moving elements like sketch lines etc. I immediately thought that however it was a few elements in which case the way I mentioned before could go well.... .


You may have found yourself in my own case where you have an infinite number of elements to deal with at the same time. ......
I suppose, for example, to select all the curves of your assembly that you want to enclose in a layer you used the "find" command from the edit menu? ?
 
I found myself in your own situation....
We do everything by step and try to figure out how they work with the help of someone...... .

first step
you have to take on the toolbar "graphic property" with which you manage the layers.... take the last drop-down menu and choose other layers.... in the window that opens to choose new..... will be created layer1 (and we will give it the value 1)... double click to rename it for example "curve" so we will manage the curves of our assembly.... made that in the drop-down menu of the toolbar "proprieta' graphics" will also appear the layer "curve" (inverted from the number 1)

second step
change the display filter value. ....
to change the filter go to display filters tools and in the screen that opens choose "visible only the current layer"

third step
you have to move all the curves of our assembly on the previously created layer (layer 1 curve)
then edit->trova.......... in the opening window choose the second telescope "find and select" in the drop-down menu type choose the option "from the element" and click on any curve on the screen, in this way all the curves will be selected....important.... in the "find" drop-down menu specific in which environment you want to go looking for curves.......... for example you can go to take all the visible curves on the screen or you can also go to take all the curves included in the hidden space....click on ok to select all the curves that on the screen will become red.... at this point go on any of these curved right-click properties'-> graphics and from layer choose the curved layer (number 1)....

at this point with a normal cad would be all right but with cad no...... .
In fact, if you go to the graphic menu and choose layer 1 (i.e. curves) one would expect everything to disappear and only remain the layer with curves....... catia instead (and here would be the case that someone gave me confirmation) displays on the screen both the selected layer and "all entities that do not have a membership layer". ......
Let's see how to proceed now... .
I moved all my curves to layer 1.... in the drop-down menu of graphic property I choose other layers and create a new one (layer 2) and select it......... Since filter layer is set to "view the current" on the screen will remain all the objects except the curves, in fact the layer 2 (which at the moment is empty) and all the objects that do not belong to any particular layer......... so you have to move all the objects to layer 2....... go on edit->trova and "find and select"....... leave everything with asterisks but in the drop-down menu choose "visible on the screen".... all entities at this point will be selected.... right button on any of these-> properties'-> graphics and move everything on layer2.................................. at this point on layer 1 we have curves while on layer 2 we have all other entities............ .

Sorry for the unclear explanation but I managed to run the layers only in this way
 
Thank you! :biggrin:

the explanation is very clear!
I missed the part from " at this point with a normal cad it would be all right but with catia no....... "
Now I try but I think it will work!:finger:
 
The concept is that every entity must belong to a plan otherwise it always shows it...... .
Remember that for the moment it is better to work with visible objects on screen........
Once you understand the mechanism you do the same with the objects of the invisible space......
If you can run it all later, maybe we try to use the filters so that only the layers containing curves and those contenting the planes may appear.... even here catia does not forget having adopted a really hostical mechanism
 
Bye.
I level them at the end of work to geometric groups (when model in surfaces) so that during conversion to "iges" my client does not have all geometries spaly on a single level. for the rest I find very practical geometric groups; It is certain that they must be structured according to some logic according to their needs.
greetings
 

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