su lamiera piegata

[Simonnvrg]

Good morning.
I look for tips to create the bugna in images starting from a solid sheet folded 90° with 1mm thickness using the environment part design or generative sheetmetal design.
or if there is some "truck" to bring it back from a solid already finished to what I'm modeling. thanks in advance

 

[Lettore espatriato]

Good morning.
I look for tips to create the bugna in images starting from a solid sheet folded 90° with 1mm thickness using the environment part design or generative sheetmetal design.
or if there is some "truck" to bring it back from a solid already finished to what I'm modeling. thanks in advanceView attachment 61012 View attachment 61013

frankly not model brackets of this type, so I can only indicate standard options ...

Among other things, I use v5/v6 at work, then make screenshots of what model, I miss to talk about it.

First of all, if it is a folded sheet bracket, it would be better to define it in the "sheetmetal" environment, so that the various bending parameters are maintained.

so the "normal" solution would look like this

http://catiadoc.free.fr/online/cfyugstamp_c2/cfyugstampstiffeningrib.htm

Otherwise, there are various other options, depending on what your starting situation is and what your final result is.

For example, your starting solid, is it parametric or is it a solid dead? and your final solid, how should it be if it's a solid, it's just the result of a surface thickness or do you have a whole set of part design operations?

because, depending on the above there are various options, each with its positive and negative sides.


1) Solids: Rebuild the feature with feature recognition, copy and paste the feature into your solid.

http://catiadoc.free.fr/online/catiafr_c2/fr1ugcatiafrs.htm

for complex forms becomes rognose, but at the level of a cylindrical bug, it should arrive....


2) Mixed surfaces/solids: create 2 sketches, extrusion surfaces, solids, surface thickness, add in your solid

3) solids : procedure as 2) but with prism

4) surfaces/solids : surface extracts, untrim (subdivided if it tells you that they are more than 1 ) , in the case more 'ticker should give you a quadrangular surface that you need to extrapolate , etc. etc.

As you can see, there are various possibilities to do what you have, vaguely, mentioned. The problem is, first of all, to understand what your starting point is and what your arrival point wants.

If that's a non-form cylinder, I have some doubt about his perfect printability.
ps2 that radius 1.4 mm..... ?

 

[Simonnvrg]

first of all thanks for the answer,
at the end I used the command costs stiffening in the sheetmetal environment (I was wrong to define it bugna when in reality its function is exactly what it calls the command). I did not know this modeling environment well yet I did not know that there was a special feature. I got exactly the result I wanted.
Thank you for your help