various tricks and tactics of "solidification"

[Michele_F]

Good morning to all and welcome

I'm going to ask you about the arduous problem of "solidification" of an imported geometry. the file in question had various problems both of tangency and of junction between the surfaces that I solved and currently seems not to present any imperfection.... but I do not see the "solidification" button

Have you ever found yourself in this situation? How to proceed? Is there a way to figure out what are the quilt points that don't cheer? What are you doing?

ah, the software version in question is wildfire 4 m100 (I think)

thanks to anyone who can help me (but also to others :d)

 

[mamobono]

Hi.
a parameter that you can verify is the precision of the design, sometimes changing it improves the situation

by personal experience I always send + solid formats
The best I think is stp but I send me ,x_t and then I try.

last week a stp was not about to have it solid, instead x_t at the first stroke (file from solidworks)

I probably think that much depends also on the export setting or the precision (parameter cad ) of the original design

but I accept other suggestions from what you know about + :bekle:

Hi.

 

[folle76]

the best solution that, as always, involves a minimum of study is import date doctor. take a look at the online guide on using this module for fixing imported geometries. solidification is then ensured.

 

[mini me]

It takes a beard! simple but effective
to find the opening on a surface you can try as follows:

inser­
when asked to define trajectory >select traj> bndry chain
at this point just select the quilt and automatically proposes you to select all available edges
ps this method only serves to understand where to intervene...
I hope you've been helped

 

[Michele_F]

Thank you for the answers!
x mad: import data doctor I have already used it but, mystery of mysteries, it did not work....
x mamobono: Unfortunately I have only that geometry, and also a grace: (also it is only a skin already with all the aesthetic rays (conical, variable etc.) of which most have r< thickness I must therefore copy the offsettable surfaces and re-roll the inside
x mini me: interesting! Tonight I try the beard

thanks to all for the interest :d

 

[simra]

It takes a beard! simple but effective
to find the opening on a surface you can try as follows:

inser­
when asked to define trajectory >select traj> bndry chain
at this point just select the quilt and automatically proposes you to select all available edges
ps this method only serves to understand where to intervene...
I hope you've been helped

I'm interested in this method but it's not very clear to me, I tried to use the command but how do I understand where the problem is?

 

[maxopus]

I'm interested in this method but it's not very clear to me, I tried to use the command but how do I understand where the problem is?

the "holes" appear highlighted in green.

 

[fabrizio67]

If you have the import data doctor form, you will certainly have easier life.
In his absence, he observes:

1) After importing, check whether or not the geometry check entry is on under the info menu.
Usually, the lack of solidification of the imported part is due to geometric errors.
with the module surfaces and a little patience, you usually get out.

2) If for some reason, the seam of the surfaces fails, the areas where there are openings are clearly visible.
also here, where the import data doctor module does not arrive or is not enough, I personally operate with the surface module.
two cases:
2a] you go luxury and create one or more blend surfaces you can "capture the hole" and solidify everything.
2b] the iella follows you as the cloud of puppets and then you have to try to remove the adjacent surfaces to the problematic area, rebuild them, join them and...cross your fingers and try to solidify everything.

regarding the formats from which to import the files, I agree with those who preceded me in preferring the step format and/or the parasolid; worse the iges format.

Hi.

 

[Michele_F]

If you have the import data doctor form, you will certainly have easier life.
In his absence, he observes:

1) After importing, check whether or not the geometry check entry is on under the info menu.
Usually, the lack of solidification of the imported part is due to geometric errors.
with the module surfaces and a little patience, you usually get out.

2) If for some reason, the seam of the surfaces fails, the areas where there are openings are clearly visible.
also here, where the import data doctor module does not arrive or is not enough, I personally operate with the surface module.
two cases:
2a] you go luxury and create one or more blend surfaces you can "capture the hole" and solidify everything.
2b] the iella follows you as the cloud of puppets and then you have to try to remove the adjacent surfaces to the problematic area, rebuild them, combine them and...cross your fingers and try to solidify everything.regarding the formats from which to import the files, I agree with those who preceded me in preferring the step format and/or the parasolid; worse the iges format.

Hi.

geom check was the final weapon to detect the nanometric hole between two partially tangent and partially detached surfaces :biggrin:
I had to trim the original quilt and pass a new blend to solidify

All is well what ends well, thank you for reminding me of geom cherck:biggrin: you were great:finger:

 

[zimmy]

the need to close imported surfaces and solidify is very widespread and very important.
the use of import data doctor It is fundamental because there are many features that allow to correct any inconsistencies, errors, defects of imported geometry, to recreate datum, to unite and separate surfaces, etc.

in these cases I don't think we have to go through it., stopping holes, doing surfaces, trying to fix things by hoping for good luck.

you have to proceed method (as always) with the safety of the various powerful tools made available by the import data doctor.
you need to know the specifications of iges, step to know where to intervene and why to change the acuracy. it is necessary to know why sometimes iges is not good. it is necessary to know if there are parameters of the config.pro that it is good to change if the geometry comes from a cad or another ...
it is necessary to know if another method of data sharing may be better,...
There are tricks to know where the file remains open (even if you just do not see ...).

In short, the subject is rich and complex.
the market proposes specific courses on these topics. last one day and face all these topics.

I know how to sin of conflict of interest (I therefore ask clemency to all of you) because the courses I organize them and I hold them. But it also seems important to say that because they can still be useful to many.

the forum is a place of sharing information, and when you can give me my contribution.
but here the topic cannot be treated with some simple answer.
Greetings to all.

 

[fabrizio67]

zimmy,
what you say is true, only that the import data doctor module does not possess it all and it is not that it comes away free... of the module and not even the course...
...so of necessity, virtue. .
...if you have to work with imported files 8 hours a day, there is probably no other way.. .
...if you have to work with imported files 1 time and away, maybe it is more difficult to think about buying the module...species of these times.. .

Hi.

 

[zimmy]

Hi.
to me it turns out that it is included in the foundation package.
from import feature, right-click "change definition"
and the repair functions appear under the heading "geometria" of the menu above
or with icons (probably right of the window).

 

[mamobono]

Hi.
to me it turns out that it is included in the foundation package.
from import feature, right-click "change definition"
and the repair functions appear under the heading "geometria" of the menu above
or with icons (probably right of the window).

yes

fabrizio 67 " if you have to work with imported files 1 time and away, maybe it is more difficult to think about buying the module...species of these times..."
the same situation, moreover without renewal maintenance so you arrange with what you can learn also thanks to this forum

zimmy : maybe fabrizio67 referred to this http://www.ptc.com/products/proe/frt/index.htmfeature recognition tool for pro/engineer
that unfortunately not being in maintenance I can not download
You may tell us how it is:
Thank you.

 

[zimmy]

frt ( feature recognition tool) is another thing than the idd.
It is a series of functions that allow to reconstruct an imported model recognizing geometries as extrusions, cuts, holes, series, rays, fittings, ...

from an imported model then you get a proe file with the tree model of parametric and editable features normally.
Of course it is possible to use these functions for non-complex models (it is not possible to reconstruct a double curvature surface resulting from other cad) but can be extremely useful for a good range of imported details.
work directly in part 3d environment.

for the reconstruction of imported geometries I also remember the functions of autobuildz that reconstructs the parametric 3d mathematics from a simple imported dwg.

both tools are included in the foundation.

for the wf4 the tool frt you can download from the site if you are in maintenance (and this seems to me the least ) but it is "comprehensive in the price"! . is not an additional module. in the wf5 is already directly in the foundation.

autobuildz is included in the basic package from a couple of versions.

I hope I've been clear.