componenti series

[d-prom]

Good morning, everyone.
I tried to sift the forum but found nothing about the question I want to ask.
we all know that in inventor it is possible to realize a series of components linked to a series of processes, and that the series of components will be automatically updated to the range of the processing series (classic example: series of screws linked to the series of holes). but this (at least it is what I found) only if the series of work is in one part. if it is in a set, inventor categorically refuses to create the set of components.
my case is this: I modeled a welded object that then undergoes work for removal of material, and in these cases I have the bad vice to model as it happens in reality: first the individual parts without processing, then the raw welded, then all the processing performed on the welded welded weld. processing on the individual parts only if they are really made on the individual pieces before assembling and welding. Now, on the object in question there is a series of 24 holes that will serve to fix the object on the base with as many screws. but after placing the first screw in the first hole, there is no way to make him make the series of screws tied to the series of holes, which instead other software allow.
I'm reluctant or just not possible?
I thank those who will help me in advance.

 

[Peppe]

You answered yourself.
the software recognizes only series of part-level processing and not together.

 

[d-prom]

So, if I understand, I only have two possibilities:

1) pitch and constraint all screws one by one: apart from the loss of time and crumbling of cabbasi, I have no connection between the screws and holes that host them; if I move a hole the screw follows it, but if I add or remove it I must remember to add or remove the screws (always one by one). .
2) I create a series of screws fine to itself: compared to solution 1 saving time but I completely renounce any connection between the series of screws and the series of holes.

It would be a good thing that the autodesk gentlemen stepped up, as this problem on other cads is not...

 

[Peppe]

no, in bolted connection as positioning do not use "for hole" but "concentric", in this way you can select multiple items at a time.
It's useless to say that the other cads do things that inventor doesn't do, this is and with that if he has to adapt

 

[Zac69]

Good morning, everyone.
I tried to sift the forum but found nothing about the question I want to ask.
we all know that in inventor it is possible to realize a series of components linked to a series of processes, and that the series of components will be automatically updated to the range of the processing series (classic example: series of screws linked to the series of holes). but this (at least it is what I found) only if the series of work is in one part. if it is in a set, inventor categorically refuses to create the set of components.
my case is this: I modeled a welded object that then undergoes work for removal of material, and in these cases I have the bad vice to model as it happens in reality: first the individual parts without processing, then the raw welded, then all the processing performed on the welded welded weld. processing on the individual parts only if they are really made on the individual pieces before assembling and welding. Now, on the object in question there is a series of 24 holes that will serve to fix the object on the base with as many screws. but after placing the first screw in the first hole, there is no way to make him make the series of screws tied to the series of holes, which instead other software allow.
I'm reluctant or just not possible?
I thank those who will help me in advance.

your reasoning and modeling system does not make a fold.
if the 24 holes are a series, a loophole can be to make them even on the part, but of so small diameter that you do not see. at this point the table of the solid is in place and not quoti the microphores, while the screws the constraints precisely to this series and not to that of the assemblies.

I agree with peppe. easy to criticize this compared to that, but this you have. and maybe that doesn't have something that he has.

 

[tzadik]

you can import into the file together, the parameters of the hole series from the file part.
then you can serialize your " bolted connection group" with the parameters of the set of holes.

or you can create in the asses the sketch with the positions of the holes.
then, either on the axieme or on the individual parts, use the position of the mother sketch holes (in the axieme) to drill into the individual parts (in the part file or in the axieme)... and reuse the sketch parameters to serialize your " bolted connection group".

You still have various methods to automate this.

you can also create a "bucket connection group", not connected to a hole.
the washers distance them as much as they need (... you can parameterize this distance too).
once all the elements of the " bolted connection group" are bound together (insertion, blocked).
Cops... and locked insertion... on the holes you need (this way you don't have a series... of course).

for more complex couplings you should work with ucs positioned where/how you need.
(especially when you have so many occasions that you cannot serialize)