explode and develop sheet "multibody"

[saracf]

Good morning, I created the detail that I attach starting from a simple figure that got away complicated.
I am now in "difficulty" in putting it on the table because, to illustrate it clearly to the assembler I should realize many views and sections.

the ideal solution would be to be able to show this part exploded so that the assembler can quickly understand how many and what are the pieces to assemble, moreover it would be useful also to be able to put in the table the various developments of sheet metal for the lamierista (I saw that in part, the developments are created - separately, but they are created).

I looked between the sw controls but I found nothing that allows me to put on the table the exploded or to put the developments of the various parts that make it.
Can you suggest me a command or a way to proceed or restart and redesign the various pieces as part and then assign them as together?

 

[MassiVonWeizen]

You can't explode a part.http://help.solidworks.com/2012/italian/solidworks/sldworks/t_exploded_views_in_drawings.htm

 

[MassiVonWeizen]

I would make two sheets of the part.
on one developments for the lamierist and the shape to be obtained with identification markers, on the other the carter with dimensions and positioning of the various parts for the welder using markers to identify the various parts. some section is necessary of course. and then a couple of isometric views to make the construction clearer

 

[saracf]

You can't explode a part.http://help.solidworks.com/2012/italian/solidworks/sldworks/t_exploded_views_in_drawings.htm

Hello and thank you,
Actually you can, suggest it yourself with your link (see attachments).
Now it would be enough to understand how to put on the table the various "parts" developed (same file but in separate sheets, rightly), I put on the table (view palette) do not see the classical ones/the flattened views: how did you suggest to do exactly?

 

[MassiVonWeizen]

I said... I ask the jury and the court not to take into account the last statement of the witness

I think you're gonna have to make some configurations. I saw that by activating two flattenings the file is messed up, at least at a first glance...if I can cut out some time I make a real test

 

[saracf]

I said... I ask the jury and the court not to take into account the last statement of the witness

I think you're gonna have to make some configurations. I saw that by activating two flattenings the file is messed up, at least at a first glance...if I can cut out some time I make a real test

hi, you actually gave the right suggestion to solve my first part of the problem, now miss the speech developments.
I can flatten, one by one, the parts in the "part", but when I pass to the table there does not even appear a flattened view so I can not place them on the table... maybe you say that creating various configurations where, from time to time, turn everything apart from the part to put on the table at that time, you can be able to view it even at the table?
In fact I didn't think about it, I want to try it right away, and if you have any other suggestions I will gladly accept them.

 

[xxfast]

hi, you actually gave the right suggestion to solve my first part of the problem, now miss the speech developments.
I can flatten, one by one, the parts in the "part", but when I pass to the table there does not even appear a flattened view so I can not place them on the table... maybe you say that creating various configurations where, from time to time, turn everything apart from the part to put on the table at that time, you can be able to view it even at the table?
In fact I didn't think about it, I want to try it right away, and if you have any other suggestions I will gladly accept them.

If you send it to me in the 2011 version I will take a look.:smile:

 

[sampom]

...when I pass to the table there is not even a flattened view, so I can't place them on the table... .

It's a part. multicorpo of sheet metal, the flat views do not appear directly on the table. but in part 3d the flattened configurations are created automatically (you don't need to create other "hand"), and you find them on the list of the property manager at the table:from the view palette you translate one (anywhere) of your multibody into the graphic area. with this new active view, in the prop. man. Select the button select bodies. It brings you back to the 3d where you will choose the body in sheet metal that interests you, go back to the table where always in the prop. man. the view flat repetition. your folded sheet metal body will develop automatically creating a normal flattened view: ..you can add all the developments of each body/lamiera in the same sheet.



I return to repeat myself smile:
we study all the menus well and try all the options; almost always the solutions are in front of the eyes (or under the right clik:biggrin.
For example, you may not see "correct" the flattened view, with the bending notes not on the lines and perhaps scattered in the graphic area. in this case just press the button capovolgi vista and everything comes back.
always click and try everything, quiet that doesn't break anything. .

greetings
Marco:smile:

p.s. of course the 3d of the sheet must be modeled "to perfection" (according to the precise rules of the sheet module), otherwise errors and failures of flattening will be inevitable.
other thing: better not exaggerate with the number of sheet metal bodies, the file becomes slow and heavy and the possibilities of error in the application of the functions increase. Perhaps in your case it would be safer and better manageable a "true" together.

 

[Mike1967]

I strongly pledge to work with the multi-cortpo in sheet metal, easily merges and no longer develops some details or in inserting a certain body puts another on the table.
in 2013 the multi sheet metal has improved a lot but with 2012 I gave up from a nice piece.
many times I had to save the bodies with the "Save in the part" function to avoid throwing all the file.
:smile:

 

[re_solidworks]

the explanation of sampom was exhaustive and it is easier to make than to say. I do not use the multibody of sheet metal, but I have never encountered problems in the pieces that I made / quite simple).

For the explosive, I don't know if you solved and it's not a real explosion, but you can make a configuration where, with moving bodies, positions the corpses of sheet metal as if it was an explosion. It takes a little longer but it works.

Hi.

 

[Mike1967]

...as an advertisement of hurrà said. . . Maybe mine is broken...

attach files, maybe on another pc it works... :frown:
designed with swx 2012 sp 4.

 

[re_solidworks]

...as an advertisement of hurrà said. . . Maybe mine is broken...

attach files, maybe on another pc it works... :frown:
designed with swx 2012 sp 4.

the file doesn't work because you first made the sheet and then you split it. I usually insert the feature of sheet metal at the end by converting solids into sheet metal and creating from a single solid the various components.
more than a kiss I would say a limitation, though heavy.

 

[Mike1967]

the file doesn't work because you first made the sheet and then you split it. I usually insert the feature of sheet metal at the end by converting solids into sheet metal and creating from a single solid the various components.
more than a kiss I would say a limitation, though heavy.

Yeah, but in theory it should work.
the problem is that just created develop quietly but as soon as you work, maybe adding other bodies, you mess up
began to play the rosary.
Unfortunately planning for construction sometimes you can't choose the strategy suitable for design.
I'll post you some other models.

 

[PiegatoreSolidworks]

Yeah, but in theory it should work.
the problem is that just created develop quietly but as soon as you work, maybe adding other bodies, you mess up
began to play the rosary.
Unfortunately planning for construction sometimes you can't choose the strategy suitable for design.
I'll post you some other models.

I also confirm...a similar piece designed with 2013 by many less problems (almost nothing) than 2012...I just made a try!