import stp files and edit it

[giek]

Hello, everyone. I press that I am not an experienced inventor user but I have to solve this problem: I have a spt file that contains a valve group, I should open it with inventor 2009, isolate a single valve of the four contained in the file and then be able to use it as a component in a set. Can any of you help me?

 

[stefanobruno]

I didn't find your presentation message, did I?
Go back and see if we help you.

Bye.

 

[giek]

Sorry, I didn't read the private message I was told to introduce myself. remedy immediately

 

[giek]

I have introduced myself

 

[giek]

in inventor I tried to open the file spt but after selecting the file and clicked open I appear a window with "could not insert object" though clicking on erase opens the same file with the 4 valves. at this point I selected the other 3 valves, deleted them and saved. then I tried to open a new axieme file and insert the saved valve and it looks like it works. Is there a better procedure for you?

 

[stefanobruno]

in inventor I tried to open the file spt but after selecting the file and clicked open I appear a window with "could not insert object" though clicking on erase opens the same file with the 4 valves. at this point I selected the other 3 valves, deleted them and saved. then I tried to open a new axieme file and insert the saved valve and it looks like it works. Is there a better procedure for you?

I was just suggesting you do this, you got there on your own.
when you use commercial components downloaded from the web, you should still make some adjustments.
In your specific case, I think you'll have the reference plans shot in some area that has nothing to do with the piece you need.
You should fix it, not that you can't use the file even so, but if the references are consistent, when assembling everything flows faster.
Unfortunately it is a difficult thing to explain by beating on the keyboard.
I'll stop right here if you need more tips, write.

Bye.

 

[giek]

I was just suggesting you do this, you got there on your own.
when you use commercial components downloaded from the web, you should still make some adjustments.
In your specific case, I think you'll have the reference plans shot in some area that has nothing to do with the piece you need.
You should fix it, not that you can't use the file even so, but if the references are consistent, when assembling everything flows faster.
Unfortunately it is a difficult thing to explain by beating on the keyboard.
I'll stop right here if you need more tips, write.

Bye.

Thank you very much for the answer.
when you talk about reference plans do you refer to xy xz yz plans?

 

[stefanobruno]

Thank you very much for the answer.
when you talk about reference plans do you refer to xy xz yz plans?

Yes................( dots serve to get to the minimum of characters :biggrin: )

 

[giek]

in fact the plans are a bit shifted compared to the component; If this will cause me trouble in the future I will ask you how you solved it. the fact is that the company for which I work has never designed in 3d and now wants to start creating a 3d library of the components that it uses to realize the plants. I inventor used it for a couple of exams at the university and so I have no in-depth knowledge of the program. I warn you that there will be other questions from me... Wow, the last sentence sounds like a lol threat.

 

[stefanobruno]

if you make a library you want to use in a productive way You must have put in place immediately immediately your models, later it will be too late.

 

[giek]

if you make a library you want to use in a productive way You must have put in place immediately immediately your models, later it will be too late.

Do you have any advice to give me about the axle story?

 

[stefanobruno]

Do you have any advice to give me about the axle story?

as I wrote before, it is difficult to say what to do having only a keyboard in front and imagining the object of which we speak.
if you want (and you can ), attach the file or image where you see what we are talking about, maybe with the visible plans.

 

[giek]

Can you understand something from this image? http://imageshack.us/photo/my-images/545/cattura1y.png/

 

[stefanobruno]

Can you understand something from this image? http://imageshack.us/photo/my-images/545/cattura1y.png/

I see.
What you can do is this.
Do a new set, bring in your valve and remove the attachment.
constraint your valve to the correct planes, save under the valve name (valve.iam )
do a new .ipt, close the sketch, delete it from the browser, make a derivative component pointing on the set "valve.iam ", stop the connection and save "valve.ipt ".
now you have " valve " correctly positioned.
It's longer to explain what to do.

Bye.

 

[giek]

I see.
What you can do is this.
Do a new set, bring in your valve and remove the attachment.
constraint your valve to the correct planes, save under the valve name (valve.iam )
do a new .ipt, close the sketch, delete it from the browser, make a derivative component pointing on the set "valve.iam ", stop the connection and save "valve.ipt ".
now you have " valve " correctly positioned.
It's longer to explain what to do.

Bye.

I managed to remove the fixing and move the valve by orienting it according to the reference plans but I can't understand what you wrote me later. Why do I need to open a new .ipt file, create and delete the sketch? and when you talk about component derived to what you mean? excuse ignorance

 

[stefanobruno]

and when you talk about component derived to what you mean?

your "valvola.iam" would already be valid for reuse as a standard component.
transformation into "valvola.ipt" is a matter of file management slenderness, the ipt is one while the .iam requires at least one connected .ipt, then two files.
search among the icons of the .ipt environment what is called "derived component " and then follow step by step what I wrote to you.
in my profile there is the skype icon, if you want to connect.

Bye.

 

[giek]

I think I understand. Thank you for your help. Hi.

 

[stefanobruno]

I think I understand. Thank you for your help. Hi.

bene, bene.

ciao.

 

[giek]

stefano, I try to summarize the whole procedure I followed to ask you some questions at the end:
- from inventor apro .spt file, opens a .iam file with a set of 5 valves; gate the 4 that I do not care and save with first name.iam
- at this point before moving from .iam to .ipt I want to better place my valve than the planes and reference axes; I open new axieme file (which I will call second.iam) and insert first, remove the fixing to the valve and give a couple of constraints between valve and planes and reference axes (for example I could impose the coincidence between axis z and a valve axis that I created and a mat bond between xy plane and a valve plane). except as second.iam
- I open a new .ipt file, close the sketch and use the derived component function, select second.iam and interrupt the connection except for the 5 components that make up the single valve (green leaves the icons under bodies). except as valve.ipt
- at this point if I open a new .iam file and insert the valve.ipt should appear as a single piece oriented according to the constraints.

I have a few questions about this:
- it is necessary to create second.iam or can I do the procedure of positioning regarding axes and reference plans directly on first.iam?
-when you tell me that it is necessary to reposition the various pieces regarding plans and reference boards to have a "ordered" library is because, when I have to use more pieces of the library for a larger set, big way will I know how they are inserted in the .iam file space of the axieme?
- when I give the bonds in second.iam I noticed that, for example after giving the first constraint, I have to use the wheel command element to select the two faces for the second constraint mate and so doing it seems that the first constraint I gave does not exist since the piece seems to move freely in space even if the first constraint on the premises is
- when I insert valve.ipt into a file of assemblies the valve should appear according to the constraints I gave him however at this point should no longer exist and I should be free to impose new ones, right?
- if you want to change the orientation of the piece compared to the planes and reference axes I should act in the file according to.iam but so doing I do not think it is automatically updated also in valve.ipt since I interrupted the connection, am I?
-When I got the valve.ipt file the other files could I in theory delete them?
- if you want to organize a library of the various valves used by the company (e.g. starting from a first folder with the name of the supplier and then via the subfolders of the various types of valves (to butterfly, to piston...) until you reach the individual files.ipt) I recommend using the project function or banally create this system of folders and subfolders and then save in the appropriate folders the individual ipn files? should only insert valve.ipt files or even second.iam?
I thank you in advance if you want to answer me and I apologize if I'm so heavy but I don't want to get to create the library with the various pieces and then find out that I'm wrong and have to start from scratch

 

[stefanobruno]

- it is necessary to create second.iam or can I do the procedure of positioning regarding axes and reference plans directly on first.iam?

If first is a .iam, the movements you do them directly there.

-when you tell me that it is necessary to reposition the various pieces regarding plans and reference boards to have a "ordered" library is because, when I have to use more pieces of the library for a larger set, big way will I know how they are inserted in the .iam file space of the axieme?

It is not a matter of predicting how they will be inserted, so much you can not choose until the piece is released in the .iam itself.
the usefulness of having coherent planes or axes is that you can use them as a reference to bind, disconnect (partially) from the actual shape of the piece (if the flange becomes square instead of circular it is possible that you do not lose the constraints, which with pin/hole you do not get – also this is a little difficult to explain for good, but do not worry )

- when I give the bonds in second.iam I noticed that, for example after giving the first constraint, I have to use the wheel command element to select the two faces for the second constraint mate and so doing it seems that the first constraint I gave does not exist since the piece seems to move freely in space even if the first constraint on the premises is

is right, otherwise it would be difficult to reach and select references.

- when I insert valve.ipt into a file of assemblies the valve should appear according to the constraints I gave him however at this point should no longer exist and I should be free to impose new ones, right?

exact, except the first inserted, which by default is fixed ( but you can undelete )

- if you want to change the orientation of the piece compared to the planes and reference axes I should act in the file according to.iam but so doing I do not think it is automatically updated also in valve.ipt since I interrupted the connection, am I?

exact and exact.
Before interrupting the links check the guidelines.
when you are satisfied, stop the links.

-When I got the valve.ipt file the other files could I in theory delete them?

Yes, see below.

- if you want to organize a library of the various valves used by the company (e.g. starting from a first folder with the name of the supplier and then via the subfolders of the various types of valves (to butterfly, to piston...) until you reach the individual files.ipt) I recommend using the project function or banally create this system of folders and subfolders and then save in the appropriate folders the individual ipn files? should only insert valve.ipt files or even second.iam?

while you create the library, work in a project file that you will call “commercial”, located in the “commercial” folder.
when you use created commercials, in your new project you will add the path that points to “commercial”.
if the commercials are .ipt derivatives, with the broken connection, the .iam and corresponding .ipt departure no longer serve (before incinerate everything, try the operation )