symbol diameter in side view odds

[arzigogolo]

Hello, everyone.

I am a new user of proe wildfire 5.0 and I am using it with discreet satisfaction (at least for the moment!). initially with frustration, then using it more and more (and much thanks to the explanations that I find on this great site), I am beginning to understand how it works and to use it with relative productivity.
Coming from inventor, I found myself quite flattened as he does the same things, but quite differently. I am referring in particular to the relationship between the quotas of the model, to the parameters, etc. (at least as far as I could see until now) so I found a little difficult to adapt myself, but I am doing it with passion.

to come to the sodo, although the problem may seem trivial, I would like to know if in the table setting it is possible to obtain the symbol of the diameter automatically in the quotas in the side views of a cylindrical part.
because by clicking on the horizontal lines of the cylindrical part and clicking with the central key, I get out of the quota, but then the symbol of the diameter I have to add it by hand by double click on the quota.

I would like to know precisely, if you can automatically show up as you do for the quotas in the plan view of a cylindrical part (i.e. by double click on the circular edge and then click with central button appears automatically).

I have already tried to see between previous discussions, but I couldn't find the solution.

I add an image to clarify better.

Thank you in advance.

 

[lollone]

I use wf3...but I think the principle is the same!doing so you have to insert the diameter symbol manually!
to use 100% pro-and you have to learn to work in a certain way...the odds you should avoid entering them manually! ! !
you must recover them from the solid drawn!col button exhibition/cancella.
you will find them the symbol of the diameter on the quota!
why have to quote the piece again manually if you have already done it in the construction phase of the model 3d?!? ! ! ?

 

[arzigogolo]

I use wf3...but I think the principle is the same!doing so you have to insert the diameter symbol manually!
to use 100% pro-and you have to learn to work in a certain way...the odds you should avoid entering them manually! ! !
you must recover them from the solid drawn!col button exhibition/cancella.
you will find them the symbol of the diameter on the quota!
why have to quote the piece again manually if you have already done it in the construction phase of the model 3d?!? ! ! ?

Hey, thanks for the tip! You're right, Lollone, I have to learn how to use it best, but being at first so many things I think of it as an inventor and instead the approach is different.
I had also noticed that by clicking with the right mouse button on the view it is possible to recall the quotas of the model including those with the diameter already inserted.
I was only wondering if, if necessary, there was the same possibility to insert them already with the automatic diameter symbol.

However, you gave me a valuable suggestion that I recall all the shares from the solid, thus avoiding losing time by inserting them manually.
That's how you work with a proe, anyway? i.e. recalling the quotas from the model and possibly adding other completion?

Thank you again! :smile:

 

[lollone]

Yes, you work like that!
think if you have to do an analysis of the 3d! couplings all the odds are appropriate!
Moreover, in order to put tolerances like h7 you have to enter the tolerance on the quota taken from the model!
this is the procedure that allows you not to waste time requoting the part having already done it! In addition, the quotas for the table are not lost in the event of a change.
from a bit I also use inventor and I see that for users of this program it is not normal to use the quotas of the model for the table!even if inventor allows to reason as pro-e!!!

 

[arzigogolo]

it is true what you say, even inventor allows to recall the quotas from the model, but all the times I tried to save time, in the workshop it was not good because the workers of the work of the piece wanted the quotas in a certain way (because of the machines to control numerical that they used) so there was to those who were better to quote the piece in one way rather than in another and then, at that point, I prefer not to put them back. Otherwise I would have liked to call them back from the model, you know what time savings I would have had! In addition, as you say, in case of change you do not lose quotas.
However, as a pro-pro parametric kernel is clearly superior to inventor. Just think of the possibility to dynamically change a processing: Unsurpassed!
inventor also arrived with the fusion module, but does not take into account the working history as all parametric software. If this is good or bad, I don't know.

to return to bomb, so there is no possibility to create the automatic diameter symbol with the side view?

I thank you again for the helpfulness and the good advice I do treasure and since I am still in the first arms with proes, I think I will still need your help and all those who want to give it to me.

 

[lollone]

I made a macro!
just select a quota is press the d button on the keyboard, and the suffix diameter on the quota is added!

 

[arzigogolo]

If I don't ask you too much, could you show me how you did the macro?
i.e., do you need to enter instructions in a particular programming language or just register manual operations? example: start the macro recording I double click on the quota, add the diameter symbol, click ok and stop on the macro recording?
Since I've never done it with proes, can you just tell me the steps?

Sorry about the amber.
Thank you.

 

[maxopus]

If I don't ask you too much, could you show me how you did the macro?
i.e., do you need to enter instructions in a particular programming language or just register manual operations? example: start the macro recording I double click on the quota, add the diameter symbol, click ok and stop on the macro recording?
Since I've never done it with proes, can you just tell me the steps?

Sorry about the amber.
Thank you.

the second you said, the procedure is very simple.
after recording it, remember to save it in the config.pro.

 

[lollone]

ecco alcune macro che io uso per i suffissi nelle quote.
stringhe da inserire nel config.pro

mapkey m @mapkey_nameinserisce suffisso quota m;\
mapkey(continued) @mapkey_labelsuffisso quota m;~ select `main_dlg_cur` `menubar1`1 `edit`;\
mapkey(continued) ~ close `main_dlg_cur` `menubar1`;\
mapkey(continued) ~ activate `main_dlg_cur` `edit.psh_dwg_props`;\
mapkey(continued) ~ select `mod_dim_asynch` `tab_main`1 `lay_dim_text`;\
mapkey(continued) ~ focusin `mod_dim_asynch` `txt_dim_text`;\
mapkey(continued) ~ input `mod_dim_asynch` `txt_dim_text` `m`;\
mapkey(continued) ~ input `mod_dim_asynch` `txt_dim_text` `m@`;\
mapkey(continued) ~ input `mod_dim_asynch` `txt_dim_text` `m@d`;\
mapkey(continued) ~ update `mod_dim_asynch` `txt_dim_text` `m@d`;\
mapkey(continued) ~ focusout `mod_dim_asynch` `txt_dim_text`;\
mapkey(continued) ~ activate `mod_dim_asynch` `psh_ok`;

mapkey d @mapkey_nameinserisce suffisso quota d;\
mapkey(continued) @mapkey_labelsuffisso quota d;~ select `main_dlg_cur` `menubar1`1 `edit`;\
mapkey(continued) ~ close `main_dlg_cur` `menubar1`;\
mapkey(continued) ~ activate `main_dlg_cur` `edit.psh_dwg_props`;\
mapkey(continued) ~ select `mod_dim_asynch` `tab_main`1 `lay_dim_text`;\
mapkey(continued) ~ focusin `mod_dim_asynch` `txt_dim_text`;\
mapkey(continued) ~ input `mod_dim_asynch` `txt_dim_text` `
n@d`;\
mapkey(continued) ~ focusout `mod_dim_asynch` `txt_dim_text`;\
mapkey(continued) ~ activate `mod_dim_asynch` `psh_ok`;

mapkey g @mapkey_nameinserisce suffisso quota g;\
mapkey(continued) @mapkey_labelsuffisso quota g;~ select `main_dlg_cur` `menubar1`1 `edit`;\
mapkey(continued) ~ close `main_dlg_cur` `menubar1`;\
mapkey(continued) ~ activate `main_dlg_cur` `edit.psh_dwg_props`;\
mapkey(continued) ~ select `mod_dim_asynch` `tab_main`1 `lay_dim_text`;\
mapkey(continued) ~ focusin `mod_dim_asynch` `txt_dim_text`;\
mapkey(continued) ~ input `mod_dim_asynch` `txt_dim_text` `@`;\
mapkey(continued) ~ input `mod_dim_asynch` `txt_dim_text` `@o`;\
mapkey(continued) ~ input `mod_dim_asynch` `txt_dim_text` `@og`;\
mapkey(continued) ~ update `mod_dim_asynch` `txt_dim_text` `@og`;\
mapkey(continued) ~ focusout `mod_dim_asynch` `txt_dim_text`;

 

[arzigogolo]

Wow! Thank you very much! and also to you maxopus!
These macros will be very useful to me when I have to insert the "m" symbol into the thread and "g" quotas for the supposed gas threads.
Meanwhile I tried to create my macro and it works! inserts the diameter symbol into the selected quota and works even if they select more odds. Good.
This is the text of the macro I created:

mapkey gg @mapkey_name inserts diameter symbol in the quotas\nlinear; ♪
mapkey(continued) @mapkey_labelsimbolo_diameter; ♪
mapkey(continued) ~ timer`ui desktop```ui desktop```popupmenurmbtimercb`; ♪
mapkey(continued) ~ command `procmdeditproperties`;\
mapkey(continued) ~ move `mod_dim_new_asynch` `mod_dim_new_asynch`2 9.415445 5.9394;\
mapkey(continued) ~ select `mod_dim_new_asynch` `tab_main`1 `lay_display`; ♪
mapkey(continued) ~ activate `mod_dim_new_asynch` `psh_sym_palette` ; ♪
mapkey(continued) ~ focusin `mod_dim_new_asynch````txt_dim_text`; ♪
mapkey(continued) ~ focusout `mod_dim_new_asynch````txt_dim_text`; ♪
mapkey(continued) ~ activate `sympalette` `sp_110`; ♪
mapkey(continued) ~ update `mod_dim_new_asynch` `txt_dim_text```\n@d`; ♪
mapkey(continued) ~ focusin `mod_dim_new_asynch````txt_dim_text`; ♪
mapkey(continued) ~ focusout `mod_dim_new_asynch````txt_dim_text`; ♪
mapkey(continued) ~ activate `sympalette` `close`;\
mapkey(continued) ~ focusin `mod_dim_new_asynch````txt_dim_text`; ♪
mapkey(continued) ~ focusout `mod_dim_new_asynch````txt_dim_text`; ♪
mapkey(continued) ~ activate `mod_dim_new_asynch` `psh_ok`;

It should be right because his job does.
the only thing is that when I launch the macro, one sees for a fraction of a second the opening of the window "quota property". practically is the operation I did manually when I created the macro and I added the diameter symbol.
but is it right so or should you not see the operations that have been carried out?

Last but not least, would you please just give me advice on the flight without having to open another forum?
It's just this: in drawing mode, I hid the display of reference plans, axes, points and notes because they bothered me. to save this setting and make sure that at the next beeping of the design you memorize it, what should you do? I tried to see in the config.pro, but I couldn't find the setting that interests me.
In addition I saw this old discussion, but I was not useful.http://www.cad3d.it/forum1/showthread.php?t=3219&highlight=nascondere+assi+messa+tavola Thank you.

 

[lollone]

to solve your problem (which has been faced several times) you must set on the config.pro that axes plans or other references are spending by default.
insert the following strings:
datum_display no
datum_point_display no
display_axes no
display_coord_sys no

for the macro discord is normal.

 

[arzigogolo]

to solve your problem (which has been faced several times) you must set on the config.pro that axes plans or other references are spending by default.
insert the following strings:
datum_display no
datum_point_display no
display_axes no
display_coord_sys no

for the macro discord is normal.

Oops... Thank you, I didn't see you answered me in this debate. :biggrin: